Post by woodworker171 on Nov 13, 2017 22:19:55 GMT -5
Was working on a project that I had to tile the tool paths. I ran the first 2 tool paths in tile 1 and then received this message "Error Y out of soft limit" when trying to run the third tool path. I shut the machine down, restarted it and ran the third the 3 tool path again and everything worked great.
After moving the material I ran the first 2 tool paths in tile 2 and everything worked fine. I then tried to run the third tool path in the second tile and received this message again. "Error Y out of soft limit". I shut the machine down and restarted and tried it again. Same message. So far I haven't been able to run the third tool path in the second tile. Each tile is 30" long in the Y direction but that is within the Y capabilities of my AR6 Pro.
Any suggestions will be greatly appreciated.
Thanks in advance.
Last Edit: Nov 30, 2017 22:06:32 GMT -5 by woodworker171: Found my problem
I had a similar problem 2 days ago. I re checked my tool path and found I had not turned the piece in the proper direction. Even if it looks correct, the tool path is taking the router out of the limits of the machine. Call Chad at Axiom! He will be able to assist you.
Did you ever get an answer to this? I am now having the same problem with Tiling have a piece that ix 16 wide by 70 long and I am tiling thru the Y axis at 38 inches. The first toolpath works fine but I get the Y axis out of limit error as well. I have tried turning off the machine and one, checking where the start position is set, recalculating and previewing all toolpaths, etc. No joy. As luck will have it is 5:50 and Tech Support is gone for the day.
I looked in the manual and checked to make sure it is 1X, 1Y, 1Z but no joy.
Last Edit: Nov 28, 2017 19:58:32 GMT -5 by gene35146
If I understand when you see Y999 that number is in millimeters and you convert as long as that is under like 47 inches you should be fine. I was looking for something either going negative Y or past 47 inches, does that make sense?
Playing with the simulator in GEditor on this line which is line 7
It give this error
Line 7: N60G2X25.042Y759.892I2.832J2.832 ERROR: Distance from each arc endpoint to center differs by 4.0051, more than tolerance of 0.0010.
N60: Block or sequence number G2: Clockwise circular interpolation (move in a circular arc at feed speed) Relative IJK resolves to absolute IJK = I25.042 J759.892 K-2.903 Distance from last move to center = 4.0051 Distance from this move to center = 0.0001 Arc endpoint: 25.0421, 759.8921, -2.9030 Arc center coordinates: 25.0421, 759.8920, -2.9030, radius = 0.0001 (determined by IJK) Arc angles: 225.0 to 90.0(225.1 degrees total) Time: 20:28.7 Adj Time: 23:46 V End: 1752.6
Have not had a chance to try the fixed file from Chad but essentially what he did was copy the toolpaths and select each tile and recalculate. Seems like if that works there is some error in Aspire but if you get to this you might try that fix.
Post by woodworker171 on Nov 30, 2017 22:19:59 GMT -5
I found my problem. When I set xy-0 I had not left enough room at the at the front of the machine for the router bit. When I tried to run the tool path for the second tile I received the error message "Error Y out of soft limit". Chad told me that this error was saying there was not enough room for the router bit. I had assumed it was telling me that I didn't have enough room at the far end of the table. Then I realized when I set my xy-0 I had left the y axis at 1. Once Chad mentioned this I moved my xy-0 up the bed about 1 inch and everything worked correctly. I had allowed for a 1/4" over lap in the tile and having left the Y at 1 there wasn't enough room at the near end of the board.
I always leave about 2 inches at the front and back to clamp and was using a .25 inch bit so I am sure that is not it. I ultimately saved the file twice and manually tiled it as two files to get it to run. The duplicating toolpath didnt actually run as it then creates 4 toolpaths not 2. I have done this before but it was with an older version of VCarve. I am pretty sure this is some issue with Aspire so I have submitted it to Vectric but havent got a definative answer yet.
This seems like the answer to the problem. Will have to try this and see. This is from Vectric Support.
One common thing with a Tiling toolpaths is that the second one might move into the Negative Y by the Radius of the tool to ensure a clean Tile cut. This might be putting the toolpath beyond the edge of your machines movement range. If you Offset the Datum position on your machine a short way along the Y Axis, this should free up the machine to safely make this small move into Negative Y to cut your tile correctly.
Let me follow this up to maybe close out my thoughts on this as I have been going round and round with Vectric support. Let me explain what I have figured out.
Let's say that you have an AR8 pro with a maximum y travel distance of a little under 48 inches and you want to cut a simple profile rectangle that is 60 inches by 20 inches. You draw the box, you decide to use a .25 inch bit and you tell it to tile at 30 inches and generate the two tiled toolpaths and you are off and running right?
Nope, not exactly. On the second tiled toolpath it wants to move the tool to what would be a negative .025 just 25/100s of an inch in order to make sure that where the two tiles join the sides of the rectangle will get completely cut. Bang you now have a problem that movement of .025 so that it can position the .25 toolbit correctly now results in a negative y movement on the axis. Now what might be the answer to all of this?
Take the same scenario and home the machine to x 0, y0. Then move up the y axis by the width of the tool that you will use and now set that as the new home position temporarily. So you can not have the start of the work being exactly on the x0, y0 position you must have some room at the front of your project. You would then cut the first tile from that position and when you get ready to start the 2nd tile you would also have to return to that position as well. I think this is the same problem that woodworker171 posted about above and the final fix. The whole split into two duplicate two paths I think was a red herring.
The reason I was able to tile without any issues before was I was cutting panels for a cabinet and the break was between the pins on a side so there was nothing exactly on the tile line. If you have at least the width of the tool you select at the tile then you wont have this problem anyway.
Last Edit: Dec 5, 2017 9:28:43 GMT -5 by gene35146